[ADINA] ADINA의 Connector Element를 이용한 Advanced Structural Modeling
Advanced Structural Modeling with ADINA’s Connector Element
It is often desirable to replace complex or expensive solid element models with structural elements possessing equivalent mechanical responses. Beam, truss, and spring elements are a few familiar examples, and they can be used in many circumstances. However, the response of bushings, bearings, ball joints, or structural components with general geometries, etc. can be more complex, with different and potentially nonlinear stiffness and/or damping responses in different degrees of freedom. Such cases cannot be modeled accurately with traditional structural elements. ADINA’s new connector element was developed to provide users with a convenient tool for these cases, and many others.
The connector element is a 2-node large displacement generalized spring/damper element with linear or nonlinear material properties. Furthermore, the connector element possesses a user-defined convecting local coordinate system such that for rigid body motions, the relative nodal positions and orientations (local displacements and rotations) remain unchanged, and the element’s internal forces transform with the rigid body motions. In other words, the response of the structure being modeled will be preserved under rigid body motions. For example, a connector element modeling a shock absorber will predict the same response (relative to its attached local coordinate system) regardless of its orientation.
The following example demonstrates how a 3D solid finite element model of a light truck suspension component, complete with connecting bushings, can be replaced using 3 connector elements which provide the equivalent structural response at a small fraction of the computational cost.
Figure 1 illustrates the components under consideration in relation to the vehicle’s front axle. The inset in Figure 1 details these components.
Figure 1 Suspension components under consideration, with detailed inset. The inset shows the 3D solid model of the radius arm (grey) and its attached bushings (blue). The radius arm is steel and linearly elastic. The bushings are rubber (large strain hyperelasticity, incompressible).
Joint Connector Elements
A connector element may be used to model linear or nonlinear joint behavior, with separate, arbitrary responses for each of its six local degrees of freedom. The element’s nodes may be initially separated or coincident, and the user may arbitrarily define the element’s local coordinate system and undeformed state.
Figure 2 shows a cutaway view of the rear rubber bushing and steel shaft connection. As the connection undergoes large relative translations and rotations, the rubber bushing experiences large strains. Also, because the steel and the rubber materials both possess high bulk moduli, the steel shaft undergoes moderate bending. By modeling this interaction, it is possible to obtain an accurate response of the joint.
Figure 2 Cutaway view of the 3D solid model used to model the rear bushing/radius arm connection. This model is used to obtain the nonlinear force-displacement responses, which can then be used to define a corresponding connector element. In this case, the connection is modeled in a way that captures the coupled effects of the actions of the bushing and the shaft. By prescribing a set of translations and rotations at the rigid link master to articulate the connection, the response is obtained from the reactions at the master node.
Given a set of prescribed displacements and rotations, a corresponding set of reaction forces and moments can be obtained from the 3D solid finite element model. These displacements and reactions can then be used to define the equivalent connector element’s nonlinear force-displacement responses in each of its six local degrees of freedom. Figure 3 (top) shows the rear bushing/radius arm connection as it articulates under prescribed translations and rotations. The equivalent connector element is shown (Figure 3, bottom) undergoing the same prescribed translations and rotations.
Figure 3 3D solid model (top) used to model the rear bushing/radius arm connection as it articulates. The response of the connection is obtained from the force and moment reactions at the master node of the rigid link, shown in Figure 2. An equivalent connector element (bottom) is used to model the rear bushing/radius arm connection. The triads at each node clearly show the relative translations and rotations of the element’s nodes.
Figure 4 shows the comparison of the responses predicted by the 3D solid model and the connector element model. As can be seen, the responses of the 3D-solid model and the equivalent connector element are identical. The response for the front bushing is obtained in a similar manner.
Figure 4 Comparison of the response curves for the rear bushing joint. The solid curves are the responses obtained from the 3D solid model, and the open circles are for the responses of the connector element. Due to symmetry, only 4 sets of motions are required to capture the connection’s response. The 1-direction is oriented along the long axis of the connection, and the 2-direction is any radial direction.
Matrix Connector Element
The connector element also allows for the user to directly specify the structure’s stiffness matrix relative to the structure’s local coordinate system (which the user can specify in several ways). The connector element will provide the same response (with respect to its attached coordinate system) for any orientation or position as it moves in space (the connector element is always a large displacement/rotation element).
It is easy to extract the stiffness matrix from an arbitrary structure by subjecting it to a series of small prescribed displacements at its 2 points of attachment (these points of attachment correspond to the connector element’s nodes). Each prescribed displacement in the local degree of freedom provides 12 reaction forces and moments, which gives a column in the 12x12 stiffness matrix. Figure 5 illustrates the process of interrogating the structure and populating the stiffness matrix.
Figure 5 Illustration of the process used for obtaining the 12x12 stiffness matrix [K] corresponding to a connecting structure. The connecting structure (in this case, the radius arm) is assumed to possess a linear response. It is attached at two locations (in this case, surfaces), which will correspond to local nodes 1 and 2 of the connector element. Each node is connected to the proximate connecting surfaces of the structure via a rigid link spider (not shown here, for clarity). Each node is then subjected to a series of small displacements and rotations while the other node is held fixed. During loading, the force and moment reactions at local nodes 1 and 2 are obtained. By dividing each of the 12 reactions by the prescribed displacement, a column of the stiffness matrix is obtained. The motions have been greatly exaggerated for clarity.
Complete Connector Element Model
Figure 6 shows the connector element model of the assembly as it is subjected to the same time-dependent loads as the 3D solid model shown at the top of this page. Figure 7 shows the responses predicted by each model to the same time-dependent applied force.
Figure 6 Connector element model of the radius arm and attached bushings subjected to a time-dependent loading sequence. The fixed node corresponds to the anchoring point of the rear bushing. Three connector elements are used: 1) to model the rear bushing/radius arm connection (green); 2) to model the linear response of the radius arm (magenta); and 3) to model the front bushing/radius arm connection (cyan).
Figure 7 Response of the connector element model of the suspension assembly compared to that of the 3D solid model. The response of the 3D solid model is shown with the solid curves and the response of the connector element model is shown with open circles.
As the suspension articulates and the component undergoes finite rotations (as it would when the rear bushing bends), the connector element’s local coordinate system follows the elements and the response properly transforms. As seen, practically the same results are obtained, but the connector element model is obviously far more computationally efficient.
This example demonstrates how the connector element can be used to model linear or nonlinear elastic behavior. The connector element can also be used to model linear or nonlinear damping behavior. For example, coil-over shock assemblies can easily be modeled using a single nonlinear connector element possessing both stiffness and damping responses. The user may also directly specify damping matrices.
The connector element is the latest addition to ADINA’s advanced nonlinear capabilities, and its general formulation and flexibility give the user easy access to powerful and increasingly efficient modeling techniques.
Connector element, bushings, nonlinear structural response, element stiffness matrix, large displacements, large rotations, vehicle suspensions
New [pSeven] DATADVANCE를 NAFEMS World Congress 2019에서 만나보세요 !
ablemax | 15:48 | 추천 0 | 조회 4
[BruceEYE] 인공지능 기반 영상분석 플랫폼 BruceEYE 적용 예시
ablemax | 2019.04.09 | 추천 0 | 조회 128
프로모션사례2 : 피닉스 큐브셋 Thermal Modeling (아리조나 주립대)
ablemax | 2019.03.27 | 추천 0 | 조회 84
프로모션사례1 : 대학 설계 경진대회 포뮬라1 스타일 경주자동차 파워저장장치 해석 (위스콘신대)
ablemax | 2019.03.27 | 추천 0 | 조회 93
[SINDA./FLUINT] Thermal Desktop 튜토리얼 영상 모음 2
ablemax | 2019.02.14 | 추천 0 | 조회 162
[SINDA./FLUINT] Thermal Desktop 튜토리얼 영상 모음 1
ablemax | 2019.02.14 | 추천 0 | 조회 203
[SINDA/FLUINT] Expanded Online Class Offerings Part 1 : Introduction to FloCAD
ablemax | 2019.01.24 | 추천 0 | 조회 236
[SINDA/FLUINT] 2019년 1월 뉴스레터 안내 (Veritrek: Extending Thermal Desktop..)
ablemax | 2019.01.24 | 추천 0 | 조회 227
[pSeven] Learn about UAV multidisciplinary optimization with pSeven innovative technologies
ablemax | 2018.12.17 | 추천 0 | 조회 284
[SINDA/FLUINT] 열해석 전문툴 Thermal Desktop을 이용한 ‘배관 내의 결빙 모델링’ 소개
ablemax | 2018.12.13 | 추천 0 | 조회 248